Autodesk Fusion 360 Quiz: Move Copy

10 questions · exam conditions

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Move CopyQuestion 1 of 10

A component occurrence is grounded at the assembly origin. A designer selects it in Move/Copy and enters a translation of $25\text{ mm}$ , but the component must remain in the new location as an assembly occurrence.

What should the designer do before applying the translation?

Unground the component, and then use Move/Copy to translate the component occurrence.

Activate the component, and then use Move/Copy to translate only its solid body.

Leave the component grounded, and enable Create Copy before entering the translation.

Convert the component to a body, and then use Move/Copy to translate the body.

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Autodesk Fusion 360 Quiz

Autodesk Fusion 360 Quiz: Move Copy

Practice Move Copy in Autodesk Fusion 360 with focused quiz questions that help you check what you know, review explanations, and build confidence with test-style prompts.

What this quiz covers

This quiz focuses on Move Copy, giving you a quick way to practice the rules, question types, and explanations that matter most for Autodesk Fusion 360.

How to use this quiz

Try each quiz question before looking at the correct answer. Use the explanations to review missed ideas, then come back to similar questions until the pattern feels familiar.

All questions

Question 1

What should the designer do before applying the translation?

Unground the component, and then use Move/Copy to translate the component occurrence. (correct answer)
Activate the component, and then use Move/Copy to translate only its solid body.
Leave the component grounded, and enable Create Copy before entering the translation.
Convert the component to a body, and then use Move/Copy to translate the body.

Explanation: Whenever you see a question about moving components in Fusion 360, the key distinction to keep in mind is the difference between a grounded component and a free one. A grounded component is pinned to the assembly origin — it has zero degrees of freedom, so any translation you attempt will be blocked or ignored because the ground constraint overrides the move. To actually reposition a component occurrence and have it stay in its new location, you must first remove that ground constraint. That's exactly what answer A describes: unground the component first, then use Move/Copy to apply the

25\text{ mm}

translation. Without the ground, the occurrence is free to move, and its new position becomes its assembly position — no copy needed, no workaround required. Answer B is wrong because activating a component and moving only its solid body changes the body's position within the component's local space, not the component's placement in the assembly. This creates an internal offset, not an assembly-level translation. Answer C is wrong because enabling Create Copy duplicates the component into a new occurrence at the translated position — the original grounded occurrence stays where it is. The designer wants to move the existing occurrence, not create a second one. Answer D is wrong because converting a component to a body destroys the component structure (hierarchy, joints, and references), which is a destructive and unnecessary step just to perform a simple translation. As a study tip: on Fusion 360 questions, always ask yourself whether a constraint (like ground) would prevent the intended action — resolving the constraint is usually step one.

Question 2

The center of a body is initially at global coordinates $(12,-8,5)\text{ mm}$ . One Move/Copy operation translates it $20\text{ mm}$ in the negative X direction. A second operation translates it $14\text{ mm}$ in the positive Y direction.

What are the body's final global coordinates?

$(-8,-22,5)\text{ mm}$ , because both entered distances are treated as negative offsets.
$(32,6,5)\text{ mm}$ , because the X distance is added to the initial coordinate.
$(-8,6,5)\text{ mm}$ , because the signed translations affect X and Y independently. (correct answer)
$(-20,14,5)\text{ mm}$ , because the translation values replace the original coordinates.

Explanation: When working with Move/Copy operations in Fusion 360, you need to think of translations as signed offsets added to existing coordinates — each axis updates independently, and untouched axes remain unchanged. Starting at

(12, -8, 5)\text{ mm}

, the first operation moves the body

20\text{ mm}

in the negative X direction, so you subtract 20 from the X coordinate:

12 + (-20) = -8

. The second operation moves

14\text{ mm}

in the positive Y direction, adding 14 to Y:

-8 + 14 = 6

. The Z coordinate is never touched, so it stays at

5

. That gives a final position of

(-8, 6, 5)\text{ mm}

, confirming that C is correct. A is wrong because it assumes both translations become negative offsets — the Y translation is explicitly positive, so you add 14, not subtract it. This reflects a misreading of direction signs. B makes the opposite error with X, treating "negative X direction" as though it means adding 20 instead of subtracting, which would give

32

for X — the wrong sign entirely. D represents a fundamental misconception: translation values are offsets, not replacements. If the values replaced the coordinates, the whole concept of a starting position would be irrelevant, which is never how Fusion 360 (or vector math) works. A useful rule of thumb: in any CAD translation question, always frame your work as

\text{new coordinate} = \text{old coordinate} + \text{signed offset}

, axis by axis. If an axis isn't mentioned in the operation, its value doesn't change.

Question 3

A body has the correct orientation but is in the wrong location. A vertex on the body must land exactly on a vertex of another body, and the moved body must not rotate.

Which Move/Copy method most directly produces the required result?

Use Point to Point, selecting the body vertex first and the destination vertex second. (correct answer)
Use Rotate, selecting the two vertices as the endpoints of the rotation axis.
Use Free Move, dragging the rotation rings until the two vertices appear coincident.
Use Translate, entering the destination vertex coordinates as the translation distances.

Explanation: When working with Move/Copy in Fusion 360, the key distinction to keep in mind is what geometric constraint the task requires. Here, you need a pure translation — no rotation, just a positional shift that snaps one vertex precisely onto another. That's exactly what the Point to Point method is designed for. Point to Point (answer A) lets you select a source point on the body and a destination point on another body, and Fusion calculates the exact translation vector needed to bring them together. The body moves without any rotation, which perfectly satisfies both conditions in the problem: correct orientation preserved, vertex aligned exactly. Answer B, Rotate, is wrong by definition — the problem explicitly states the body must not rotate. Selecting two vertices as rotation-axis endpoints would also create an arbitrary spin rather than a positional correction. Answer C, Free Move, relies on manually dragging the body using on-screen handles and rotation rings. Even if you could visually approximate coincidence, this method is imprecise and depends on snapping behavior rather than exact geometric selection. It also risks accidental rotation while dragging, violating the "no rotation" constraint. Answer D, Translate, sounds plausible because translation is the right motion type. However, it requires you to manually enter XYZ distance values — meaning you'd first have to calculate the coordinate difference between the two vertices. That's an indirect, error-prone workflow. Point to Point does this automatically by letting Fusion measure the delta for you. Study tip: On Fusion 360 questions, whenever a task involves snapping one geometric feature precisely to another without rotation, Point to Point is almost always the most direct tool — it eliminates manual calculation entirely.

Question 4

A lever body must rotate around the centerline of an existing cylindrical hole. The body's default manipulator is not located on that centerline, and the lever must not translate during the operation.

Which Move/Copy workflow is the most appropriate?

Choose Rotate, select the hole's cylindrical axis or a coincident construction axis, and enter the angle. (correct answer)
Choose Free Move, retain the default pivot, and drag one of the planar translation arrows.
Choose Point to Point, select opposite points on the hole, and enter the required angle.
Choose Translate, select the hole centerline as the direction, and enter the angular value.

Explanation: When working with Move/Copy in Fusion 360, the critical question to ask yourself is: what is my pivot point, and am I rotating or translating? This question tests whether you understand how to define a custom rotation axis so that a body spins in place around a specific geometric feature. Because the lever must rotate around the cylindrical hole's centerline without any translation, you need precise control over both the type of motion and the pivot location. Option A is correct because selecting Rotate lets you explicitly define the axis of rotation — in this case, the hole's cylindrical face axis or a construction axis coincident with it — and then enter an exact angle. The body rotates purely around that centerline with zero translation, which is exactly what the scenario demands. Option B fails because Free Move keeps the default manipulator pivot, which is not on the hole centerline. Dragging a translation arrow also introduces linear movement, violating the "must not translate" constraint. Option C is a trap — Point to Point is a translation mode that moves a body so one point aligns with another; it does not perform angular rotation around an axis, and selecting "opposite points on the hole" would simply shift the body, not spin it. Option D reveals a common misconception: Translate moves a body linearly along a direction vector. Entering an angular value into a translation field is nonsensical — Translate has no angular input. Study tip: On Move/Copy questions, always match the motion type (rotate vs. translate) to the goal first, then verify whether the pivot/axis can be explicitly set to the required geometric feature.

Question 5

Design history is enabled. A body was relocated by a recorded Move/Copy feature using a translation of $18\text{ mm}$ . The required offset is later revised to $23\text{ mm}$ , and the timeline should clearly represent the intended design value.

What is the best way to implement the revision?

Delete the body and create a copied body placed directly at the revised offset of $23\text{ mm}$ .
Add a second Move feature with a translation of $23\text{ mm}$ in the same direction, keeping the first feature unchanged.
Add a second Move feature with a translation of $5\text{ mm}$ in the same direction and leave the first feature unchanged.
Edit the existing Move feature and change its translation from $18\text{ mm}$ to $23\text{ mm}$ . (correct answer)

Explanation: When working with Fusion 360's parametric timeline, the key principle is editing intent — your timeline should clearly communicate the designed value, not accumulate a chain of incremental corrections. Whenever a recorded feature needs revision, ask yourself: should I reflect the true design value, or just patch over it? The cleanest solution here is D: double-click the existing Move/Copy feature in the timeline and update the translation directly from

18\text{ mm}

23\text{ mm}

. This preserves a single, readable feature whose value matches your design intent exactly. Fusion 360 will recompute all downstream features accordingly — that's the power of a parametric, history-based workflow. A is a destructive approach. Deleting the body eliminates all history associated with it and breaks any downstream dependencies, which is far too drastic for a simple value change. B adds a second Move feature of

23\text{ mm}

, which would result in a cumulative translation of

18 + 23 = 41\text{ mm}

— not the intended

23\text{ mm}

. This is a classic arithmetic trap: the new feature stacks on top of the old one rather than replacing it. C is mathematically aware (

18 + 5 = 23\text{ mm}

), but it clutters the timeline with two features where one suffices. A future reviewer — or future you — must mentally add the values to understand the actual offset, which defeats the purpose of a clean parametric history. Study tip: On Fusion 360 questions, always prefer editing an existing parametric feature over adding compensating features. A clean timeline with self-evident values is both best practice and the most commonly tested correct behavior.

Question 6

An ungrounded component is repositioned in an assembly. Fusion indicates that the component has a pending positional change. The designer wants that new occurrence position recorded in the parametric design rather than discarded.

What should the designer do after verifying the new location?

Choose Revert Position so the pending change becomes the component's recorded location.
Choose Capture Position so the current component location is stored in the design history. (correct answer)
Ground the component immediately so the pending move is converted into a body-level feature.
Activate the component so its current assembly location becomes its internal origin position.

Explanation: When working with assemblies in Fusion 360, you need to understand how the software tracks component positions relative to design history. Fusion 360 uses a parametric timeline, meaning positional changes must be explicitly committed to be preserved — simply moving a component doesn't automatically record that change. When you move an ungrounded component, Fusion 360 flags it with a pending positional change, essentially saying "something has moved, but it hasn't been saved to the timeline yet." To commit that new location into the design history, you use Capture Position — which is exactly what option B describes. This command tells Fusion 360 to record the component's current location as a timeline event, making it part of the parametric design and reproducible if you roll back and replay history. Option A is backwards — Revert Position does the opposite of what you want. It discards the pending move and returns the component to its previously recorded location, throwing away your change rather than keeping it. Option C is a misconception about grounding: grounding locks a component in place relative to the assembly origin, but it does not convert a pending move into a recorded feature or save positional data to the timeline the way Capture Position does. Option D confuses assembly context with component origin — activating a component lets you edit it internally, but it has no effect on committing an assembly-level positional change. A useful tip: whenever Fusion 360 shows a pending change indicator on a component, think of it as an "unsaved draft." Capture Position is your save button for assembly locations in the parametric timeline.

Question 7

A mounting unit is organized as one Fusion component containing two solid bodies, a construction axis, and a sketch. The entire unit must be translated while preserving the relative positions of all its contents.

Which Move/Copy setup best accomplishes the relocation?

Set Move Object to Bodies, select both solid bodies, and translate them together.
Set Move Object to Components, select the mounting unit, and translate the component. (correct answer)
Set Move Object to Faces, select exterior faces from both bodies, and translate them.
Set Move Object to Sketch Objects, select the sketch, and translate its geometry.

Explanation: When working with Fusion 360's Move/Copy dialog, the key question to ask yourself is: what level of the hierarchy do I need to move? Fusion organizes designs into components, bodies, sketches, and construction geometry — and moving at the wrong level can leave parts of your design behind. Here, the mounting unit is a component containing multiple elements: two solid bodies, a construction axis, and a sketch. The only way to relocate all of these together — preserving their relative positions — is to move the component itself. When you set Move Object to Components and select the mounting unit, Fusion treats the entire container as one entity and translates everything inside it uniformly. That's why B is correct. A is tempting but flawed: moving bodies individually (or even together) only relocates the solid geometry. The construction axis and sketch remain at their original positions, breaking the spatial relationships within the unit. C makes the problem worse — translating faces via the Faces option performs a push/pull-style deformation on the solid bodies rather than relocating them. You'd distort the geometry, not move it. D targets only the sketch geometry. Even if you translated the sketch correctly, the two solid bodies and the construction axis would stay put, leaving the component's contents misaligned. A useful rule of thumb: if everything inside a container must move together, move the container — not its contents. On Fusion 360 questions involving assemblies, always look for the option that operates at the highest appropriate level of the design hierarchy.

Question 8

A body's reference point begins at global coordinates $(5,0,0)\text{ mm}$ . The timeline first applies a Move/Copy translation of $10\text{ mm}$ in positive X. A later Move/Copy feature rotates the body by $180^\circ$ about the global Z axis through the origin.

Where is the reference point after both features are evaluated in timeline order?

$(-5,0,0)\text{ mm}$ , because only the original coordinate is affected by the rotation.
$(15,0,0)\text{ mm}$ , because a full half-turn changes orientation but not position.
$(5,0,0)\text{ mm}$ , because the rotation occurs before the translation is evaluated.
$(-15,0,0)\text{ mm}$ , because the translated location is then rotated about the origin. (correct answer)

Explanation: Whenever you see a question involving sequential Move/Copy features in Fusion 360's timeline, think about order of operations: each feature is applied to the result of all previous features, not to the original position. Here's the math. The reference point starts at

(5,0,0)

mm. The first Move/Copy translates it

+10

mm in X, placing it at

(15,0,0)

mm. The second Move/Copy then rotates that point

180^\circ

about the global Z axis through the origin. A

180^\circ

Z-axis rotation negates both X and Y coordinates:

(x,y) \rightarrow (-x,-y)

. Applying that to

(15,0,0)

gives

(-15,0,0)

mm — confirming D is correct. A is wrong because it applies the rotation only to the original coordinate

(5,0,0)

, ignoring that the translation already moved the point to

(15,0,0)

before the rotation occurs. The timeline is sequential, not parallel. B confuses rotation's effect on orientation with its effect on position. A

180^\circ

rotation absolutely changes the position of any point not sitting exactly at the center of rotation. Since the point is at

(15,0,0)

, not at the origin, it moves dramatically. C reverses the timeline order — it imagines the rotation happens first and the translation second. In Fusion 360, features are evaluated top-to-bottom in the timeline, so the translation always precedes the later rotation. Study tip: When tackling timeline-order questions, literally trace the point through each feature in sequence. Never jump ahead or apply operations simultaneously — Fusion 360's parametric timeline is strictly sequential.

Question 9

A rigid body's reference point is $30\text{ mm}$ from a selected rotation axis. Relative to that axis, the point begins at $(30,0,0)\text{ mm}$ . Move/Copy rotates the body by positive $90^\circ$ about the positive Z axis, using the displayed axis direction.

Where will the reference point be relative to the rotation axis after the move?

$(0,30,0)\text{ mm}$ , because positive rotation carries positive X toward positive Y. (correct answer)
$(0,-30,0)\text{ mm}$ , because positive rotation carries positive X toward negative Y.
$(30,30,0)\text{ mm}$ , because rotation adds the radius to the Y coordinate.
$(30,0,0)\text{ mm}$ , because rotating a rigid body does not relocate its points.

Explanation: When a question involves rotating a point about an axis, think in terms of the right-hand rule and standard rotation conventions. In a right-handed coordinate system, a positive rotation about the Z axis sweeps the positive X axis toward the positive Y axis — this is the foundational rule that unlocks this entire problem. Starting at

(30, 0, 0)\text{ mm}

, the point sits on the positive X axis at radius

r = 30\text{ mm}

. Applying the 2D rotation formula for

\theta = 90°

x' = r\cos(90°) = 30 \cdot 0 = 0

y' = r\sin(90°) = 30 \cdot 1 = 30

The new position is

(0, 30, 0)\text{ mm}

, confirming that A is correct. Positive rotation carries positive X toward positive Y — exactly what the right-hand rule predicts. B describes a clockwise (negative) rotation, which would give

(0, -30, 0)

. This is the most common trap: confusing positive and negative rotation direction. C is physically nonsensical — rotation keeps the point at a fixed radius from the axis; it never adds the radius to a coordinate. If you see an answer that changes the distance from the axis during a pure rotation, eliminate it immediately. D is a fundamental misunderstanding: rotating a rigid body absolutely repositions its points in space — only the relative distances between points within the body stay fixed. As a study tip, always sketch the XY plane and mark positive X. Ask yourself: "Which way does positive Z rotation sweep?" That quick mental sketch will save you from the B trap every time.

Question 10

A model contains one solid body representing a spacer. A second spacer body is required in the same component, translated $40\text{ mm}$ along the X axis, while the original body remains in place.

Which Move/Copy settings create the required result in one operation?

Select the spacer component, enable Create Copy, and suppress the original occurrence afterward.
Select the spacer body, disable Create Copy, and apply the $40\text{ mm}$ translation.
Select the spacer body, enable Create Copy, and apply the $40\text{ mm}$ translation. (correct answer)
Select one spacer face, enable Create Copy, and apply the $40\text{ mm}$ translation.

Explanation: Whenever you see a Move/Copy question in Fusion 360, ask yourself two things: what object am I acting on, and do I need the original to stay put? Those two factors together determine the correct settings. The Move/Copy command behaves very differently depending on whether Create Copy is enabled. Without it, the selected geometry simply relocates — the original disappears from its starting position. With it, Fusion 360 duplicates the geometry and moves the copy, leaving the original untouched. For this scenario, you need two spacer bodies: the original at its current position and a new one translated

40\text{ mm}

along the X axis. That means you must select the body, enable Create Copy, and apply the translation — exactly what C describes. One operation produces both bodies simultaneously. A is wrong for two reasons: you should select a body, not a component (components carry additional structure), and suppressing the original afterward is an unnecessary extra step that contradicts the "one operation" requirement. B selects the correct object type (the body) but disables Create Copy, so the operation simply moves the original

40\text{ mm}

— you end up with one body in the new position and nothing at the original location. D selects only a single face rather than the entire body; moving a face pushes that face's geometry, distorting the solid rather than copying it. A useful rule of thumb: body = the geometry you want to duplicate; Create Copy = preserve the original. If a question mentions keeping the original and adding a new instance, both conditions must be satisfied simultaneously.